ID-range 90000-90249

90002 - 90005
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	3
	Solution	Class	8	Restart of NC-control necessary.

90008	Selection of TRC within circular motion block.
	Description	After selection of tool radius compensation there must follow a linear block, a circular block is not possible.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Modification of the NC-Program
	Error type	1, Error message from NC-program.

90009 / 90010
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90011	Block memory for non-relevant channel blocks engaged.
	Description	Blocks without any informations about movement are non-relevant channel blocks for the tool radius compensation. Example of non-relevant channel block: M-Function The number of the sequence of non-relevant channel blocks is greater as the reserved block memory.
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Modification of the NC-Program. Interrupt the sequence of non-relevant channel blocks without movement-information through a channel block with these movement-information.
	Parameter	%1:	Upper limit value [-]
			Number of the possible non-relevant blocks in sequence.
	Error type	1, Error message from NC-program.

90012
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90013	Deselection of TRC within circular motion block.
	Description	After deselection of tool radius compensation there must follow a linear block, a circular block is not possible.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Modification of the NC-Program
	Error type	1, Error message from NC-program.

90014	Deselection of TRC not permitted using direct selection.
	Description	It is not possible to deselect the tool radius compensation again after the first motion block when direct selection is choosen. Error example %wrk_90014.err N10 G00 X0 Y0 Z0 N20 V.G.WZ_AKT.R=5 N30 G01 X10 Y10 F1000 N40 G41 G138 N50 G01 X80 N60 G40 N70 G01 X90 Y0 N99 M30 Corrected example: %wrk_90014.cor N10 G00 X0 Y0 Z0 N20 V.G.WZ_AKT.R=5 N30 G01 X10 Y10 F1000 N40 G41 G138 N50 G01 X80 N60 G139 G40 N70 G01 X90 Y0 N99 M30
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Modification of NC-Program: 1. Possibility: use indirect deselection of tool radius compensation (corrected example) 2. Possibility: insert an aditional motion block before direct deselect of tool radius compensation.
	Error type	1, Error message from NC-program.

90015	Change of selection mode not permitted using direct selection.
	Description	It’s not possible to change the side of tool radius compensation after the first motion block when using direct selection of tool radius compensation.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Modification of NC-Program: 3. Possibility: use indirect selection of tool radius compensation 4. Possibility: insert an additional motion block before changing the side of tool radius compensation.
	Error type	1, Error message from NC-program.

90016	Change of selection mode not permitted at circular motion block.
	Description	A circular motion block after changing the selection mode of the tool radius compensation is not possible. After changing the selection mode of the tool radius compensation there must be a linear motion block.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Modification of NC-Program
	Error type	1, Error message from NC-program.

90017	Tool radius greater than (or same as) contour radius.
	Description	The radius of the used tool is bigger or the same as the radius of the programmed contour.
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Use a tool with a smaller radius. The radius should be smaller as the radius of the programmed contour.
	Parameter	%1:	Actual value [-]
			Radius of the contour
		%2:	Actual value [-]
			Radius of the used tool.
		%3:	Actual value [-]
			Difference of circle radius and radius of the used tool
		%4:	Lower limit value [-]
			Minimal difference
	Error type	1, Error message from NC-program.

90018	Difference between radius of start circle and end circle exceeds range.
	Description	With the programming circles in the tool radius compensation two radius one are compared with one another. First radius is the distance of the circle centre point from the starting point of the circle, second is the distance of the circle centre point from the programmed endpoint of the circle. The difference of the two radius exceeds the permissible upper limit.
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Check and modify the programmed circle parameter in the NC program. If necessary increase accuracy of circle programming.
	Parameter	%1:	Incorrect value [0.1 µm or 0,0001°]
			Difference of the distance between circle and starting point and distance between circle centre and termination point.
		%2:	Upper limit value [0.1 µm or 0,0001°]
			Maximal value of the difference
		%3:	Actual value [0.1 µm or 0,0001°]
			Distance: circle centre point – starting point of circle
		%4:	Actual value [0.1 µm or 0,0001°]
			Distance: circle centre point – end point of circle
	Error type	1, Error message from NC-program.

90019	Contour error due to compensation motion within linear motion block.
	Description	For comprehending the contour damage in linear blocks the direction of the programmed movement block is compared with the direction of the corrected movement block. If the directions are opposed to one another then this signifies a contour damage. The movement opposite to the programmed direction is called compensatory movement. A cause can be a relatively small motion block, e.g. smaller than the tool radius, which leads with the calculation of the equidistant course to contour error.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Use tool with smaller radius
	Error type	1, Error message from NC-program.

90020 - 90025
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90026	De-/selection without valid feed rate.
	Description	It does not exist valid value for the feed rate. With tangential selection or deselection in rapid traverse the feed rate must have a valid value.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Modification of NC-Program, programming of the feed rate
	Error type	1, Error message from NC-program.

90027 - 90030
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90031	Tool radius exceeds range at channel block sequence circle-circle.
	Description	Tool radius exceeds range at channel block sequence circle-circle, a calculation of the intersection of the circles is not possible
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Use of a tool with smaller radius
	Parameter	%1:	Actual value [0.1 µm or 0,0001°]
			Available width of tool diameter
		%2:	Lower limit value [0.1 µm or 0,0001°]
			Tool diameter
		%3:	Actual value [0.1 µm or 0,0001°]
			Diameters of the first programmed circle and/or sector of a circle
		%4:	Actual value [0.1 µm or 0,0001°]
			Diameters of the second programmed circle and/or sector of a circle
		%5:	Actual value [0.1 µm or 0,0001°]
			Distance of the circle centre points
	Error type	1, Error message from NC-program.

90032 - 90035
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90036	Tool radius exceeds range at channel block sequence circle-circle.
	Description	A calculation of intersection of the segments of the circles is not possible.
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Use of a tool with smaller radius
	Parameter	%1:	Actual value [0.1 µm or 0,0001°]

		%2:	Upper limit value [0.1 µm or 0,0001°]

	Error type	1, Error message from NC-program.

90037
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90038	Compensation motion within circular motion block.
	Description	The corrected circular angle is more largely than the original angle, due to an contour error. Balance movements in circular motion blocks are recognized through controlling the circular angle Using a tool with a smaller radius there will be no contour error, because the corrected course does not create a balance movement.
	Reaction	Class		2	Abort of the NC program processing.
	Solution	Class		6	Use tool with smaller radius
	Parameter	%1:	Actual value [0.1 µm or 0,0001°]
			Corrected circular angle
		%2:	Upper limit value [0.1 µm or 0,0001°]

	Error type	1, Error message from NC-program.

90040
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90041	Removed non relevant channel block.
	Description	Remove a non relevant channel block, because the distance of the motion block is less then the minimal limit.
	Reaction	Class	1	Warning
	Solution	Class	1
	Error type	1, Error message from NC-program.

90042 - 90045
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90046	Radius within circular motion block is 0.
	Description	The radius of the circular motion block is zero.
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Modification of NC-Program
	Parameter	%1:	Actual value [-]

		%2:	Lower limit value [-]

	Error type	1, Error message from NC-program.

90047	Difference of tool radius within circular motion block.
	Description	Changing the tool radius when tool radius compensation is selected is not possible if a circular motion block is following.
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Modification of NC-Program
	Parameter	%1:	Actual value [0.1 µm or 0,0001°]
			Difference of tool radius
		%2:	Limit value [0.1 µm or 0,0001°]
			Maximal difference of tool radius
	Error type	1, Error message from NC-program.

90048
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90049	Program ends within selected state.
	Description	It’s not possible to end program without deselect tool radius compensation. Error example: %wrk_90049.err N10 G00 X0 Y0 Z0 G17 N20 V.G.WZ_AKT.R=5 N30 G01 X10 Y10 F10000 N40 G41 N50 G01 X80 N60 G01 X90 Y20 N80 G01 X90 Y0 N99 M30 Corrected example: %wrk_90049.cor N10 G00 X0 Y0 Z0 G17 N20 V.G.WZ_AKT.R=5 N30 G01 X10 Y10 F10000 N40 G41 N50 G01 X80 N60 G01 X90 Y20 N70 G40 N80 G01 X90 Y0 N99 M30
	Reaction	Class	2	NC program processing is continued
	Solution	Class	6	Use a tool with a smaller radius
	Error type	1, Error message from NC-program.

90050	Received NC_KANL_CTRL within selected state.
	Description	NC commands which cause an emptying of the channel are not permissible while TRC is active. The NC command #FLUSH for example is one of these commands. The error also occurs when TRC is apparently already deselected while using direct or indirect mode of deselection. Test program with occurrence of the error: N100 G139 ( indirect mode of selection) N110 G41 G01X100 Y100 ( selection of TRC ) N120 G01 X140 Y20 F2000 N130 G03 X160 Y40 R20 N140 G01 X200 N150 G01 X220 Y20 N160 G40 ( deselection of TRC ) N170 #FLUSH N180 G01 X0Y0 Corrected test program : N100 G139 (indirect mode of selection) N110 G41 G01X100 Y100 (selection of TRC ) N120 G01 X140 Y20 F2000 N130 G03 X160 Y40 R20 N140 G01 X200 N150 G01 X220 Y20 N160 G40 G01 X0 Y0 (deselection of TRC ) N170 #FLUSH The deciding difference of the two test routines is the position of the motion block after the deselection with the command G40.Because only after this movement the distance of the tool to the programmed contour is abolished again. To avoid the error with direct or indirect deselection of TRC there must be a movement block between G40 and the NC command which causes the emptying of the channel. [PROG Chapter: Flushing NC channel]
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Modification of NC program similar to the corrected test program
	Error type	1, Error message from NC-program.

90051 - 90056
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90057	Adapting of feed rate impossible within G05 (tool radius exceeds range).
	Description	An alignment of the feed rate within the G05 block is impossible, the tool radius is too big.
	Reaction	Class		1	NC program processing is continued.
	Solution	Class		1	Use a tool with a smaller radius
	Parameter	%1:	Actual value [0.1 µm or 0,0001°]
			Radius of the tool
		%2:	Actual value [0.1 µm or 0,0001°]
			Theoretical radius of the tangential determined path
		%3:	Actual value [0.1 µm or 0,0001°]
			Corrected radius of the tangential path
		%4:	Lower limit value [0.1 µm or 0,0001°]
			Limit of the corrected radius
	Error type	1, Error message from NC-program.

90059 / 90060
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90062	No intersection point could be calculatet between straight line and circle.
	Description	At a transition from a linear to circular motion block no intersection for the equidistant course could be determined, the tool radius is too large.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Use of a tool with smaller radius.
	Error type	1, Error message from NC-program.

90063	Movement block converted from circular to linear (tool radius too big).
	Description	At a transition from a circular to a linear motion block no intersection for the equidistant course could be determined, the tool radius is too large.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Use of a tool with smaller radius.
	Error type	1, Error message from NC-program.

90064	Movement block converted from circular to linear (tool radius too big).
	Description	The circular motion block is converted to a linear motion block. Reason for this conversion is that the corrected circle radius is close zero. The cause for it is a too large tool radius
	Reaction	Class		1	NC program processing is continued.
	Solution	Class		1	Use a tool with a smaller radius
	Parameter	%1:	Actual value [0.1 µm or 0,0001°]
			Corrected radius of the circular motion block
		%2:	Lower limit value [0.1 µm or 0,0001°]

	Error type	1, Error message from NC-program.

90065	Compensation movement found, activate contour masking process.
	Description	For comprehending the contour damage in linear blocks the direction of the programmed movement block is compared with the direction of the corrected movement block. If the directions are opposed to one another then this signifies a contour damage. The movement opposite to the programmed direction is called compensatory movement. A movement like this was recognized [PROG - Chapter: Limits of WRK] and the process of contour outline fading is actived. The principle of the outline fading out consists of removing the loop of the corrected course. In addition the outline fading out buffers a certain number of the tool radius compensation of corrected sentences. If the tool radius compensation recognizes a balance movement with active outline fading out, she marks the motion block and continues with the calculation of correction.
	Reaction	Class	1	Abort of the NC program processing
	Solution	Class	1	1. Possibility: Modification of NC-Program 2. Possibility: use a tool with a smaller radius
	Error type	1, Error message from NC-program.

90066	Compensation movement found, impossible to activate cont.mask.-process.
	Description	A balance movement was recognized, the outline fading out process cannot not be activated. The radius of the used tool is too large, the tool radius compensation cannot create a connected equidistant contour.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Use a tool with a smaller radius
	Error type	1, Error message from NC-program.

90067 - 90073
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90074	EF CONT_MASK: Compensation movement could not be removed.
	Description	The contour masking process is not able to calculate intersection of the contour. This is the cause for overflow of an internal buffer. Suggestion : Modification of the contour or using a tool with a smaller radius
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Modification of NC-Program
	Parameter	%1:	Upper limit value [-]

	Error type	1, Error message from NC-program.

90075
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90076	Conversion from circular to linear in contour masking.
	Description	Conversion of a circular motion block to a linear motion block because of falling below the minimum limit of movements.
	Reaction	Class		1	Warning
	Solution	Class		1
	Parameter	%1:	Actual value [-]
			Number of converted block
	Error type	1, Error message from NC-program.

90077	A loop was removed from the contour masking.
	Description	Detection of a loop throughcontour masking. Reason for the loop is a recognized balance movement through the direction reversal between programmed and corrected motion block.
	Reaction	Class		1	Warning
	Solution	Class		1
	Parameter	%1:	Actual value [-]

		%2:	Actual value [-]

	Error type	1, Error message from NC-program.

90079 - 90085
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90087	Program end in state ready of EF contour masking.
	Description	At the end of program contour masking is still ready. Suggestion: Deselection of contour masking with G140 before end of program
	Reaction	Class	1	NC program processing is continued.
	Solution	Class	1	Modification of NC program
	Error type	1, Error message from NC-program.

90088	Program end during active contour masking process. (contour error).
	Description	At the end of program contour masking process is still active. Insert an additional motion block, this allows the contour masking process the calculation of an intersection point of the contour. Following the deselection of the contour masking and the tool radius compensation before the end of the program.
	Reaction	Class	3	Abort of the NC program processing
	Solution	Class	6	Modification of NC-Progam
	Error type	1, Error message from NC-program.

90090	Clear buffer during active contour masking process. (contour error).
	Description	The use of the instructions for emptying the channel (# FLUSH) are with active tool radius compensation forbidden and thus also during selected contour masking.
	Reaction	Class	3	Abort of the NC program processing
	Solution	Class	6	Modification of NC-Program
	Error type	1, Error message from NC-program.

90091 - 90097
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	3
	Solution	Class	8	Restart of NC-control necessary.

90098	EF CONT_MASK: Deselection of WRK while contour masking process is active.
	Description	Deselection of tool radius compensation without deselection of contour masking before.
	Reaction	Class	1	NC program processing is continued.
	Solution	Class	1	Modification of NC-Program: Deselection of contour masking before deselection of tool radius compensation
	Error type	1, Error message from NC-program.

90099	EF CONT_MASK: Deselection of contour masking while process is active.
	Description	Deselection of contour masking although a balance movement was recognized. The balance movement caused the activation of the contour masking process. A balance movement is a movement, which is reverse the programmed direction.
	Reaction	Class	3	Abort of the NC program processing
	Solution	Class	6	Modification of NC-Program: 1. Possibility: Using a tool with a smaller radius to hint the balance movement 2. Move the deselection of the contour masking in NC-Program
	Error type	-

90100	EF CONT_MASK: Block buffer full and no more block output possible.
	Description	The contour masking process is not able to calculate intersection of the contour. This is the cause for overflow of an internal buffer. Suggestion : Modification of the contour or using a tool with a smaller radius
	Reaction	Class		1	NC program processing is continued.
	Solution	Class		1	Modification of NC-Program
	Parameter	%1:	Actual value [-]

	Error type	1, Error message from NC-program.

90101
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90102	Invalid #INFO-Parameter.
	Description	Internal used command
	Reaction	Class		1
	Solution	Class		1
	Parameter	%1:	Incorrect value [-]

		%2:	Lower limit value [-]

		%3:	Upper limit value [-]

	Error type	1, Error message from NC-program.

90103 - 90106
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90107	Selected G237 without enabling this functionality.
	Description	Using the command G237 selection and deselection of perpendicular tool radius compensation without enabling this functionality.
	Reaction	Class	2
	Solution	Class	6
	Error type	1, Error message from NC-program.

90109	Number of nonrelevant blocks was exceeded.
	Description	The number of not-relevant blocks, which are buffered with perpendicular selection and deselection, has been exceeded. Not-relevant blocks are blocks without movement information, like for example Techno functions.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	6	Modification of NC-Program
	Error type	1, Error message from NC-program.

90110 / 90111
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90112	Block 2 intersect the course of block 1.
	Description	During the transition of blocks from linear to circular or from circular to linear an overlap of the blocks arises. Both blocks have two common points and includes a surface, which cannot be worked on with active tool radius compensation.
	Reaction	Class		1	NC program processing is continued.
	Solution	Class		1	Check and modify the course of contour in the NC program
	Parameter	%1:	Actual value [-]
			Block number of the first motion block
		%2:	Actual value [-]
			Block number of the second motion block
	Error type	1, Error message from NC-program.

90114	During active inner corner selection the number of buffered blocks was exceeded.
	Description	The number of buffered blocks between selection and deselection of tool radius compensation using inner corner selection exceeds the permissible limit.
	Reaction	Class		2	Abort of the NC program processing.
	Solution	Class		3	Check and modify NC program. Reduce the number of the buffered blocks.
	Parameter	%1:	Upper limit value [-]
			Maximum number of blocks, which can be buffered.
	Error type	1, Error message from NC-program.

90115	During active inner corner selection changing side of selection is not permissible.
	Description	During active inner corner selection of TRC changing the side of selection is not permissible.
	Reaction	Class		2	Abort of the NC program processing.
	Solution	Class		3	Check and modify NC program. Remove the inadmissible G function.
	Parameter	%1:	Block number [-]
			Number of the inadmissible programmed G function
	Error type	1, Error message from NC-program.

90116	No relevant motion block available.
	Description	Using inner corner selection there is no motion block programmed, which contains movement information between selection and deselection of TRC.
	Reaction	Class	1	NC program processing is continued.
	Solution	Class	1	Check and modify the NC program.
	Error type	1, Error message from NC-program.

90117 / 90118
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90119	The programmed contour is not closed.
	Description	With inner corner selection of TRC the following contour must be closed. Closed contour means that the endpoint of block of selection must be identical with the endpoint of the last programmed point before deselection of TRC. Single blocks and contours with only two motion blocks could not be selected with this methode.
	Reaction	Class		2	Abort of the NC program processing.
	Solution	Class		6	Check and modify the first and the last motion while TRC is active. Programming single blocks or contours with only two motion block change the selection mode, using perpendicular selection mode.
	Parameter	%1:	Incorrect value [0.1 µm or 0,0001°]
			Distance of the endpoint of block of selection to the endpoint of the last motion block before deselection of TRC.
		%2:	Upper limit value [0.1 µm or 0,0001°]
			Upper limit of distance.
	Error type	1, Error message from NC-program.

90120 - 90122
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90123	Contour error through selection point of TRC.
	Description	The position of the selection point of TRC is proved when using inner corner selection. The examination contains a measuring of the distance between the selection point and the programmed contour elements. The distance have to be greater than the tool radius. With the occurrence of the error the distance was less than the tool radius.
	Reaction	Class		2	Abort of the NC program processing.
	Solution	Class		6	Check and modify the NC program either through correction the point of selection of TRC or correction of the concerned contour element. A further possibility is to use a tool radius with a smaller radius.
	Parameter	%1:	Block number [-]
			Blocknumber of the concerned contour block.
		%2:	Block number [-]
			Blocknumber of the selection block.
		%3:	Incorrect value [0.1 µm or 0,0001°]
			Distance between the concerned element of contour and the the selection point of TRC.
		%4:	Lower limit value [0.1 µm or 0,0001°]
			Minimum distance corresponds to the current tool radius.
	Error type	1, Error message from NC-program.

90124	Single full circle as closed contour is not permissible.
	Description	While inner corner selection is active there are two motion blocks programmed between selection and deselection of TRC.The second motion block is a full circle.Programming of a full circle represents a closed contour, is however not permitted.
	Reaction	Class	2	Abort of the NC program processing.
	Solution	Class	6	Check and modify the NC program. Use the perpendicular mode of selection of TRC or correct the contour.
	Error type	1, Error message from NC-program.

90125	Length of the selection block with inner corner selection is less than tool radius.
	Description	The length of the linear motion block after the inner corner selection of TRC is less than the tool radius. The position of the point at the TRC is selected is reason for it. This point is too close at the programmed contour.
	Reaction	Class		2	Abort of the NC program processing.
	Solution	Class		6	Check and modify the position of the point where the TRC is selected.
	Parameter	%1:	Block number [-]
			Number of the block where TRC is selected.
		%2:	Incorrect value [-]
			Length of the selection block.
		%3:	Lower limit value [-]
			Minimum length of selection block.
	Error type	1, Error message from NC-program.

90126	The side of selection of TRC is wrong.
	Description	The side of selection which was programmed is wrong. To arrive at the equidistant path the tool has to cross the programmed contour. In this case the contour is damaged.
	Reaction	Class	2	Abort of the NC program processing.
	Solution	Class	6	Correct the side of selection.
	Error type	1, Error message from NC-program.

90127	During active inner corner selection changing the tool radius is not permissible.
	Description	Changing the tool radius while inner corner selection of the TRC is active is not permitted.
	Reaction	Class		2	Abort of the NC program processing.
	Solution	Class		3	Modify the NC program. Modify the tool radius either before selection of the TRC or after the deselection of the TRC.
	Parameter	%1:	Block number [-]
			Number of the block the change of tool radius happened.
		%2:	Expected value [-]

		%3:	Actual value [-]

	Error type	1, Error message from NC-program.

90128	Inadmissible intersection between motion block and selection block.
	Description	With active inner corner selection the motion blocks between selection anddeseletion of TRC are examined for intersections with the starting block. With this examination an intersection of the blocks arose, which leads to the injury of the contour.
	Reaction	Class		2	Abort of the NC program processing.
	Solution	Class		6	Check and modify the NC program. Correct the position of the point of selection to modify the block of selection.
	Parameter	%1:	Block number [-]

		%2:	Block number [-]

	Error type	1, Error message from NC-program.

90129
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90130	Angle exceeds upper limit while inner corner selection of TRC is active.
	Description	With inner corner selection of the TRC the transition angle between selection block and the first motion block is examined. By the first motion block one understands the block, with which the distance of the tool radius to the programmed course is manufactured. For this transition angle exist an upper limit, this limit was exceeded.
	Reaction	Class		2	Abort of the NC program processing.
	Solution	Class		3	Check and modify the point of selection of TRC.
	Parameter	%1:	Incorrect value [-]
			Transition angle between block of selection and the first motion block.
		%2:	Upper limit value [-]
			Upper limit of transition angle.
	Error type	1, Error message from NC-program.

90131	Compensation movement of the TRC selection block not allowed.
	Description	The first motion block after selection of TRC is marked as a compensation block, this is not allowed. A cause for it is either a too short movement of the block after the selection of TRC or a too large tool radius. Using the command #FLUSH CONTINUE in NC program the complained motion block is placed direct before the #FLUSH CONTINUE command. The cause for this behaviour is that the TRC gives out the NC_KANAL_CTRL before the complained motion block. This motion block the TRC needs to calculate the following intersection point. Is this motion block marked as balance movement the contour masking could not balance the complained motion block.
	Reaction	Class	3	Abort of the NC program processing.
	Solution	Class	3	Check and modify the NC program and the used tool. Use a tool with a smaller radius. Using #FLUSH CONTINUE move the command in NC program.
	Error type	1, Error message from NC-program.

90132	The data exceeds range of data format.
	Description	Data exceeds the permissible range of data.
	Reaction	Class		2	Abort of the NC program processing.
	Solution	Class		6	Check and modify the NC-Program.
	Parameter	%1:	Incorrect value [-]

		%2:	Lower limit value [-]

		%3:	Upper limit value [-]

		%4:	Actual value [-]
			Corresponding block number in NC program
	Error type	1, Error message from NC-program.

90133	The coordinate of the corrected point is outside of the permissible range.
	Description	The tool radius compensation calculates coordinates of the equidistant course . The error occurs when the coordinate of the corrected circle centre point exceeds the permissible range of data format.
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Check and modify the NC-Program
	Parameter	%1:	Incorrect value [-]
			Calculated coordinate
		%2:	Lower limit value [-]

		%3:	Upper limit value [-]

		%4:	Block number [-]
			Corresponding block number in NC program
		%5:	Logical axis number [-]
			Logical number of axes
	Error type	1, Error message from NC-program.

90134	The coordinate of the corrected center is outside of the permissible range.
	Description	The tool radius compensation calculates coordinates of the equidistant course . The error occurs when the coordinate of the calculated termination point exceeds the permissible range of data format. The exceeding of the data format also occur with one in the tool radius compensation generated transition block, if its corrected termination point exceeds the data format. Example: When cutting 2 linear channel blocks with extremely small angle between the blocks the intersection of the equidistant ones can deviate extremely far from the original programmed intersection, in extreme cases crosses it the limit value of the permissible range.
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Check and modify the NC-Program
	Parameter	%1:	Incorrect value [-]
			Calculated coordinate
		%2:	Lower limit value [-]

		%3:	Upper limit value [-]

		%4:	Block number [-]
			Corresponding block number in NC program
		%5:	Logical axis number [-]
			Logical number of axes
	Error type	1, Error message from NC-program.

90135 / 90136
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90137	Contour error due to selection block.
	Description	The distance of the point of selection of TRC to the second motion block of contour after the selection is less than the tool radius.This means a damage of the contour.
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		3	Check and modify the NC-Program. Move the popint of selection of TRC.
	Parameter	%1:	Block number [-]
			Corresponding block number in NC program.
	Error type	1, Error message from NC-program.

90144
	Description	This error message informs about internal states, error solutions and the place of error in the source.Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

90145	EF CONT_MASK: Deselection of TRC with mode G239 while contour masking process is active.
	Description	Deselection of TRC with active mode G239 without deselection of contour masking before. At the moment of deselection of TRC the contour masking process tries to find an intersection point to protect the contour against damaging.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	3	Modification of NC-Program: 3. Possibility: Using a tool with a smaller radius to hint the balance movement 4. Move the deselection of the contour masking in NC-Program
	Error type	1, Error message from NC-program.

90146	Program end during active inner corner selection.
	Description	Using the TRC mode inner corner selection G238 [PROG - G238] in the NC program a program (M30) end was programmed in the active state. This is not permitted because the contour between the commands G41/42 and G40 must be closed. The active state of inner corner selection will be quit with the deselection of TRC. A motion block after the command G40 is necessary to deselect TRC.
	Reaction	Class	2	Abort of the NC program processing
	Solution	Class	3	Modification of NC-Program:
	Error type	1, Error message from NC-program.

90147	Tool radius is greater than the programed radius of the full circle.
	Description	The programmed radius of the full circle is smaller than the radius of the used tool.This is not permitted.
	Reaction	Class		2	Abort of the NC program processing
	Solution	Class		6	Modification of NC program or usage of a tool with a smaller radius.
	Parameter	%1:	Actual value [0.1 µm or 0,0001°]
			Programmed radius of the full circle
		%2:	Actual value [0.1 µm or 0,0001°]
			Used tool radius
	Error type	1, Error message from NC-program.

90148 - 90150
	Description	This error message informs about internal states, error solutions and the place of error in the source. Please give the complete error message data to the CNC manufacturer.
	Reaction	Class	2
	Solution	Class	8	Restart of NC-control necessary.

See also

Troubleshooting classes