Parameters
All reference cycle parameters containing geometrical descriptions of the object to be milled must be transferred for deburring (see Programming example).
Required input parameters
Input parameters | Description |
@P100 | Reference cycle as character string |
Only one parameter must be defined from the following list. The other parameter is calculated from the specified parameter and the chamfer geometry data. We recommend specifying the tool radius of the milling cutter used in the reference cycle (@P104). The resulting uniform tool offset to the workpiece edge results in a uniform chamfer. However, if the machining depth is specified, it can lead to an uneven chamfer since the radius of the previous milling cutter is not included.
Input parameters | Description |
@P1 | Reference plane (absolute) |
@P2 | Retraction plane (absolute) |
@P3 | Safety clearance in Z (relative to reference plane/machining height) |
@P4 | Machining depth If this parameter is specified, it can lead to an uneven chamfer since the radius of the previous milling cutter is not included. |
@P104 | Tool radius of the milling cutter used in the reference cycle (corresponds to radial tool offset to the workpiece edge during chamfer milling) If the chamfer milling cutter radius is smaller than this tool radius, the parameters must be defined in @P4. |
In addition, only one parameter must be defined from the following list. The other parameter is calculated internally from the specified parameter and the point angle of the chamfer cutter (@P103).
Input parameters | Description |
@P101 | Chamfer depth |
@P102 | chamfer width |
Optional input parameters
Input parameters | Description |
@P103 | Tool point angle Default value = 90 degrees |
@P105 | Feed rate for machining Default value = Active feed rate at cycle call |
@P106 | Feed rate for infeed in Z Default value = Active feed rate at cycle call |
It is recommended to use the Syntax check.to verify whether the input parameters are correctly assigned.
