Parameterisation
Required input parameters
Input parameters | Description |
@P1 | Reference plane (absolute) |
@P2 | Retraction plane (absolute) |
@P3 | Safety clearance in Z (relative to reference plane/machining height) |
@P4 | Pocket depth (relative to reference plane) |
@P5 | Maximum infeed in Z |
@P6 | Maximum infeed in XY (Maximum V.G.WZ_AKT.R is recommended to avoid residual material) |
@P50 | Identification number of the pocket contour |
Optional input parameters
Input parameters | Description |
@P7 | Pitch of plunge helix Default value = 10% of tool radius |
@P8 | Radius of plunge helix Default value = 50% of tool radius |
@P15 | Finishing allowance at base Default value = 0 |
@P16 | Finishing allowance at edge Default value = 0 |
@P20 | Feed rate for roughing for milling in the XY plane (specified in mm/min, inch/min) |
@P21 | Feed rate for roughing in Z (specified in mm/min, inch/min) |
@P22 | Feed rate for finishing for milling in the XY plane (specified in mm/min, inch/min) The default value is the feed rate for roughing |
@P23 | Feed rate for finishing for infeed in Z (specified in mm/min, inch/min) The default value is the feed rate for finishing for milling in the XY plane |
@P25 | Spindle speed for finishing (specified in rpm) Default is the spindle speed at cycle call |
@P30 | Machining direction "ClimbMilling" or 0: Down milling (default) "UpCutMilling" or 1: Up milling |
@P31 | Machining mode: "Roughing" or 1: Roughing "Finishing" or 2: Finishing "Roughing+Finishing" or 3: Roughing and finishing (default value) |
@P32 | Feed mode in Z 1: vertical 2: helical (default) |
@P135 | Maximum infeed in XY for edge finishing Default value is the maximum infeed in XY for roughing |
@P170 | Maximum infeed in XY for base finishing Default value is the maximum infeed in XY for roughing |
@P171 | Feed rate for plunging in previously milled areas Default value is the feed rate for roughing for the infeed in Z |
@P183 | Maximum path with full wrap-around before tool is re-plunged. Caution: On contours with islands and bottlenecks, full wrap-arounds may occur above this threshold. By default, the tool is not re-plunged (value = 0). Available as of CNC Build V3.1.3121.0. |
@P184 | Maximum path in idle before tool is retracted. Idling occurs when the milling cutter is positioned at the machining height at the programmed feed rate without removing any material. This parameter defines the idling distance as of which the milling cutter is retracted and repositioned. The default value is five times the tool diameter. Available as of CNC Build V3.1.3121.0. |
@P51 | Identification number of an island contour |
@P52 | Identification number of an island contour |
@P53 | Identification number of an island contour |
@P54 | Identification number of an island contour |
@P55 | Identification number of an island contour |
@P56 | Identification number of an island contour |
@P57 | Identification number of an island contour |
@P58 | Identification number of an island contour |
@P59 | Identification number of an island contour |
@P60 | Identification number of an island contour |
The function of the parameters acting in the XY plane is derived largely from the graphic below:
It is recommended to use the Syntax check to verify whether the input parameters are correctly assigned.
Parameters which mainly refer to the Z axis are displayed in the graphic below:
