Orienting tool (#TOOL ORI CS)

Syntax:

#TOOL ORI CS

Select tool orientation

The first motion block that follows #TOOL ORI CS aligns the tool in parallel to the 3rd main axis of the current PCS (W0- or MCS also possible). Programming the rotary axes in this block overrides the positions that are valid for orientation.

Orienting tool (#TOOL ORI CS) 1:
Tool aligned perpendicularly to the X-Y machining plane

Programming Example

Orienting tool

N10 B10 C20          (Slant tool)
N20 #TOOL ORI CS     (in next motion block, align tool in parallel to)
                     (the Z axis of current PCS, here MCS)
N30 X0 Y0            (Motion block in the MKS, tool is aligned B=0,C=0)
N40 B25 C-80          (Slant tool)
N50 #TOOL ORI CS     (Align tool in next motion block)
N60 #TRAFO ON        (Select RTCP)
N70 #CS ON[0,0,0,-80,-30,45]  (Transition to a rotated PCS)
N80 X100             (Motion block in PCS. align tool from N50, refers)
                     (to the MCS, i.e. B=0,C=0)
N90 #TOOL ORI CS     (Align tool in next motion block)
N100 Y150            (Too aligned in parallel to Z axis of PCS)
N110 #TOOL ORI CS
N120 Z100 B45 C10    (#TOOL ORI CS has no effect when programming)
                     (rotary axes)
N130 G18             (Change to the Z-X interpolation plane)
N140 #TOOL ORI CS    (Align tool in parallel to the Y axis)
N150 X0              (Tool aligned perpendicularly to X-Z machining plane)
M30