M/H functions with optional additional information

In NC program for M/H functions an optional additional value can be programmed, which is made available to the PLC on the technology interface in combination with the M/H function.

With the exception of the spindle functions M03, M04, M05 and M19 and the gear change functions M40-M45 to all user specific M/H functions and to the internal M functions M00, M01, M02, M17, M29 and M30 an additional value can be programmed. At this the M/H functions can be used both in channel specific and in axis specific programming syntax without any restrictions

M <expr> [ =<additive_expr> ]

or

H<expr> [ =<additive_expr> ]

M<expr> User-specific M function

H<expr> User-specific H function

< additive_expr> Optional additional value. It can be programmed directly or with general mathematical expressions as a negative or positive integer.

Programming examples

%m_h_add_fct 
(M functions with additional value) 
N10 M52=-345 
N20 M12=123 (with channel parameter m_default_outp_ax_name[12] Z) 
N30 M10=321 (with channel parameter m_default_outp_ax_name[10] S) 
N35 P1 = 567 P2 = 345 
N40 X[M54=P1] 
N50 S[REV 1000 M03 M63=-789] 
N60 M12=123 M10=321 M52=-345 X[M54=567] S[REV 1000 M03 M63=-789] 
N70 M63=-789 M52=-P2 M54=567 
N80 X[M52=-345 M54=567] Y[M63=-789] S[M05 M63=789 M54=-567] M54 M63 
(H functions with additional value) 
N110 H5=-345 
N120 H6=123 (with channel parameter h_default_outp_ax_name[6] Z) 
N130 H9=321 (with channel parameter h_default_outp_ax_name[9] S) 
N135 P3 = 567 P4 = -345 
N140 X[H7=P3] 
N150 S[REV 1500 M04 H8=-789] 
N160 H6=123 H9=321 H5=-345 X[H7=567] S[REV 1500 M04 H8=-789] 
N170 H8=-789 H5=P4 H7=567 
N180 X[H8=-789 H4 H5=-345] Y[H7=567] S[M05 H5=345 H7=567] H3 H8 
(Mixed M/H functions with additional value) 
N200 X[M52=-345 H4 H8=-789 M54=567 H5=345] H3=333 M54=444 H7=567 M63 
(M/H functions with additional value in axis speczific function(INDP)) 
N05 X[INDP G90 G01 FEED=2000 POS=555 M54=151 H8=-181] 
N999 M30=111