Selection without parallel interpolation (G200)

The internal interface between interpolator and manual operation mode is activated for the programmed axes. Spindles cannot be programmed.

Manual operation without parallel interpolation can be selected with G200.

G200 Manual operation for all axes (non-modal)

… or for some specific axes

G200 #ACHSE [ <axis_name> {, <axis_name> } ] (non-modal)

With programmed G200 the processing of the current NC-program is interrupted in the interpolator. The manual operation modes can be activated, changed and deactivated. After traversing of axes under manual operation, the continuation of the NC-program can be requested by the control statement “Continue motion” to the interpolator.

In this operating mode, the offset limits are automatically set to software limit switch positions, so that the entire software limit switch range can be traversed in the manual mode. After deselection of manual operation mode, the previous relative offset limits become valid once again.

A parallel interpolation of the axes during manual operation is not possible with G200. After the statement “Continue motion”, all the axes and operating modes are de-activated, therefore no manual operation is possible.

The decoder requests all offset- and command positions from the interpolator and sends the current command positions to all the participants in the NC channel.

If G200 is programmed without "#ACHSE[...]", then this command affects all present axes.

Programming example

.....
.....
G00 X 100 Y 100
G200 #ACHSE[X] (Manual operation without parallel interpolation)
(for X-axis)
G01 X200 Y200 F600
G01 Y 200 F500
G200 (Manual operation without parallel interpolation for all axes)
G01 Y500 Z500
.....
.....