Plausibility checks and messages

Errors and warnings

The data input parameters are checked for plausibility in the cycle before use. If values that are incorrect, unknown or otherwise unsuitable for use are detected, a message is issued in the cycle via the #ERROR command [PROG].

If this message involves an ERROR, the cycle is cancelled. If the message comprises a WARNING, the value is corrected internally in the cycle and machining is continued.

To enable precise diagnosis, the messages generated with #ERROR are described below. There are general messages, which can be generated by every cycle, and there are cycle-specific messages.

ID 13100	Safety clearance not defined.
Description	The safety clearance limits the starting movement during rapid traversing. The message is generated if the safety clearance is programmed. with zero or is not programmed at all.
Response	ERROR: Cycle is cancelled.
Remedy	Check the safety clearance and correct input parameters.
Message type	General message.

ID 13101	Multiple definition of machining depth
Description	The machining depth must be defined either as absolute or as relative. This message is generated if both data input parameters for the machining depth are assigned for absolute and relative entries.
Response	WARNING: Cycle is continued using the absolute machining depth.
Remedy	Define whether the machining depth is to be defined as absolute or relative and correct the input parameters accordingly.
Message type	General message.

ID 13102	Programmed machining depth exceeds permissible tool length.
Description	The maximum usable tool length can be entered in the tool parameters. (P[0], see Section ). In the case of a value unequal to zero, a check is made as to whether the programmed machining depth is less than the permissible usable tool length. If not, the message is generated.
Response	ERROR: Cycle is cancelled.
Remedy	Check whether the permissible tool length is defined correctly. If necessary, use a different tool for machining with a tool length that is adequate for the machining depth.
Message type	General message.

ID 13103	Number of infeed motions not defined.
Description	In the case of multiple-stage work operations up to the programmed machining depth, the number of infeed motions is checked in the cycle. The message is generated if the number of infeed motions is programmed. with zero or is not programmed at all.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the number of infeed motions and correct data input parameters.
Message type	Message from drilling or pocket milling cycle.

ID 13104	Infeed depth exceeds permissible machining stroke.
Description	The maximum permissible machining stroke can be entered in the tool parameters. (P[1], see Section 1.3). In the case of a value unequal to zero, a check is made as to whether the calculated infeed depth is less than the maximum permissible machining stroke. If not, the message is generated.
Response	WARNING: The number of infeed motions or the value of one machining stroke is adjusted within the cycle based on the maximum stroke, and the cycle is continued.
Remedy	Appropriately increase the number of infeed motions in the data input parameters or check whether the permissible machining stroked is correctly defined. If necessary, use a different tool for machining with a machining stroke that is adequate for the infeed depth.
Message type	Message from drilling or pocket milling cycle.

ID 13105	Retraction distance/holding distance not defined.
Description	During step drilling, the drilling cycle needs specification of the retraction distance or the holding distance. The message is generated if this value is programmed with zero or is not programmed at all.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the retraction or holding distance and correct data input parameters.
Message type	Message form drilling cycle.

ID 13106	Reference and retraction planes incorrectly defined
Description	In the cycle, a check is made, depending on the direction, as to whether the retraction plane lies before the reference plane, i.e. whether the retraction plane is at a greater distance from the final drilling depth than the reference plane. The message is generated if distances are equal or the retraction plane lies under the reference place.
Response	ERROR: Cycle is cancelled.
Remedy	Check the locations of the retraction and reference planes and correct data input parameters.
Message type	General message.

ID 13107	Incorrect definition of the safety clearance.
Description	In the cycle, a check is made depending on the direction and on the basis of the programmed safety clearance to determine whether the resulting safety clearance lies under the retraction plane. The message is generated if the safety and retraction planes are equal or the safety plane lies above the retraction plane.
Response	ERROR: Cycle is cancelled.
Remedy	Check the safety clearance and correct input parameters.
Message type	General message.

ID 13108	No or unknown machining direction defined.
Description	The machining direction is necessary to enable definition of the right position and effect of the safety clearance. This message is generated if no machining direction is specified.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the machining direction and correct input parameters.
Message type	General message.

ID 13109	Unknown process defined.
Description	Various processes are available for drilling. These can be selected by specifying an identification number: 0: pilot drilling (default) 1: step drilling with chip breaking 2: step drilling with chip discharging This message is generated when an identification number other than 0, 1 or 2 has been programmed in the corresponding data input parameters.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the identification number of the process and correct data input parameters.
Message type	Message form drilling cycle.

ID 13110	Machining depth not defined.
Description	The machining depth must be defined either as absolute or as relative. This message is generated if neither of the two data input parameters for the machining depth is assigned for absolute or relative entries.
Response	ERROR: Cycle is cancelled.
Remedy	Define whether the machining depth is to be defined as absolute or relative and program the input parameters accordingly.
Message type	General message.

ID 13111	Relative machining depth is zero.
Description	The machining depth must be defined either as absolute or as relative. This message is generated when the data input parameter is assigned the value zero while using a relative machining depth.
Response	ERROR: Cycle is cancelled.
Remedy	For a relative machining depth, program the data input parameter with a value unequal to zero.
Message type	General message.

ID 13120	Invalid spindle position defined.
Description	Positioning the spindle between 0°and 360°is necessary for thread tapping. This message is generated when the spindle position has been programmed outside this permissible range. Note: Optionally, the spindle position can also be assigned by default in the tool parameters (P[4], see Section ).
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the spindle position and correct input parameters.
Message type	Message from thread tapping cycle.

ID 13121	Spindle speed not defined.
Description	For thread tapping, it is necessary to specify the spindle speed to calculate the feed rate. This message is generated if the spindle speed is programmed neither in the data input parameters nor defined by default in the tool parameters (P[3], see Section).
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the spindle position and correct input or tool parameters. If both are assigned, the spindle position from the data input parameters is used.
Message type	Message from thread tapping cycle.

ID 13122	Thread pitch not defined.
Description	For thread tapping, it is necessary to specify the pitch to calculate the feed rate. This message is generated if the pitch is programmed neither in the data input parameters nor defined by default in the tool parameters (P[5], see Section ).
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the pitch and correct input or tool parameters. If both are assigned, the pitch from the data input parameters is used.
Message type	Message from thread tapping cycle.

ID 13123	Thread size not defined.
Description	If a tap with countersink (special tool (P[6], see Section 1.3) is used for machining, the metric thread size is needed to calculate countersink motion. This message is generated if the thread size is not set by default in the tool parameters (P[7], see Section ).
Response	ERROR: Cycle is cancelled.
Remedy	Check and define thread size and correct tool parameters P[7].
Message type	Message from thread tapping cycle.

ID 13140	Helical radius not defined.
Description	For helical mill drilling, it is necessary to specify the drilling radius to calculate the helical motion. This message is generated if the radius is not programmed.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the helical radius and correct input parameters.
Message type	Message from helical mill drilling cycle.

ID 13141	Helical pitch not defined.
Description	For helical mill drilling, it is necessary to specify a pitch to calculate the helical motion. This message is generated if the pitch is not programmed.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the helical pitch and correct input parameters.
Message type	Message from helical mill drilling cycle.

ID 13142	Unknown direction of rotation defined.
Description	For helical mill drilling, it is necessary to specify a direction of rotation to calculate the helical motion. This can be selected by specifying an identification number: 2: clockwise rotation (CW) 3: counterclockwise rotation (CCW) This message is generated when an identification number other than 2 or 3 has been programmed in the corresponding data input parameters.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the direction of rotation and correct input parameters.
Message type	Message from helical mill drilling cycle.

ID 13160	Pocket length not defined.
Description	For pocket milling, it is necessary to specify the first pocket side (pocket length) to calculate the countersinking motions. This message is generated if the pocket length is not programmed.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the pocket length and correct input parameters.
Message type	Message from pocket milling cycle.

ID 13161	Pocket width not defined.
Description	For pocket milling, it is necessary to specify the second pocket side (pocket width) to calculate the countersinking motions. This message is generated if the pocket width is not programmed.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the pocket width and correct input parameters.
Message type	Message from pocket milling cycle.

ID 13162	Corner radius not defined.
Description	For pocket milling, it is necessary to specify the corner radius to calculate the countersinking motions. This message is generated if the corner radius is not programmed.
Response	WARNING: Cycle is continued by using the current (milling cutter) tool radius as the corner radius.
Remedy	Check and define the corner radius and correct input parameters.
Message type	Message from pocket milling cycle.

ID 13163	Tool radius too large.
Description	A check is made as to whether the tool diameter of the current milling cutter taking into account the finishing allowance is less than the programmed width or length of the pocket. This message is displayed if the result is a violation of the pocket contour.
Response	ERROR: Cycle is cancelled.
Remedy	Use a tool with a smaller diameter for machining so that the pocket contour is not violated.
Message type	Message from pocket milling cycle.

ID 13164	Finishing allowance is zero.
Description	For pocket milling with roughing operations, it is necessary to specify a finishing allowance to calculate the countersinking motions. The message is generated if this value is programmed. with zero or is not programmed at all.
Response	WARNING: Cycle is continued. Only the roughing operation is executed. An ordered finishing operation is discarded.
Remedy	Check and define the finishing allowance and correct input parameters.
Message type	Message from pocket milling cycle.

ID 13165	Unknown milling direction defined.
Description	For pocket milling, it is necessary to specify a milling direction to calculate the countersinking motions. This can be selected by specifying an identification number: 2: clockwise milling (CW) 3: counterclockwise milling (CCW) This message is generated when an identification number other than 2 or 3 has been programmed in the corresponding data input parameters.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the milling direction and correct input parameters.
Message type	Message from pocket milling cycle.

ID 13166	Unknown machining mode defined.
Description	For pocket milling, it is necessary to specify a machining mode to calculate the countersinking motions. This can be selected by specifying an identification number: 1: roughing 2: finishing 3: roughing + finishing This message is generated when an identification number other than 1, 2 or 3 has been programmed in the corresponding data input parameters.
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the machining mode and correct input parameters.
Message type	Message from pocket milling cycle.

ID 13167	Tool radius greater than corner radius.
Description	A check is made as to whether the programmed corner radius can be manufactured with the current milling cutter. In this case, the tool radius must be less than or maximally equal to the corner radius. If not, the message is generated.
Response	WARNING: Cycle is continued by using the current (milling cutter) tool radius as the new corner radius. In this case, therefore, the corner radius of the finished pocket corresponds to the tool radius.
Remedy	Use a tool with a radius less than or equal to the programmed corner radius for machining.
Message type	Message from pocket milling cycle.

ID 13168	Incorrect definition of the overlapping factor.
Description	If the (optional) programmed overlapping factor is greater than 0%, a check is made as to whether it lies within the range up to 100%. This message is generated when the overlapping factor has been programmed outside this permissible range. Note: Alternatively, the overlapping factor can also be assigned by default in the tool parameters (P[8], see Section 1.3).
Response	ERROR: Cycle is cancelled.
Remedy	Check and define the overlapping factor and correct input parameters. If the overlapping factor is neither programmed nor assigned by default in the tool parameters, a default of 50% is set in the cycle.
Message type	Message from pocket milling cycle.

ID 13169	Corner radius is limited because it is too large.
Description	During roughing, a check is made as to whether the arising contour degenerates to a "circular pocket" when using the programmed corner radius. This message is generated if this is the case.
Response	WARNING: The corner radius is limited to a specific value so that a rectangular pocket is produced and the cycle is continued.
Remedy	If possible, reduce the corner radius and correct input parameters.
Message type	Message from pocket milling cycle.

ID 13170	Unknown plunging process defined.
Description	For pocket milling, a plunge process can be (optionally) specified to calculate the countersinking motions. In the case of a value unequal to zero, a check is made as to whether one of the following identification numbers is set: 1: plunging on an inclined path 2: vertical plunging 3: helical plunging This message is generated when an identification number other than 1, 2 or 3 has been programmed in the corresponding data input parameters.
Response	WARNING: Cycle is continued using plunging process 1 (inclined path).
Remedy	Check and define the plunging process and correct input parameters.
Message type	Message from pocket milling cycle.