Programmierbeispiel

Konturtasche fräsen

Dieses Beispiel behandelt das Fräsen einer im NC-Programm definierten Konturtasche. Es ergibt sich folgender Zyklusaufruf:

T8 D8 ( Tool data )

M6 ( Tool change )

G90 G54 M03 S6000 F5000 ( Technology data )

G00 Z100 ( Go to z start position )

G00 X0 Y0 ( Go to start position )

#VAR

V.L.SurfacePosition = 0 ( Z-Position of workpiece surface )

V.L.RetractionPlane = 100 ( Z-Position of retraction plane )

V.L.SafetyClearance = 5 ( relative value of safety clearance )

V.L.DepthOfPocket = 20 ( depth of pocket )

V.L.MaxIncrementZ = V.L.DepthOfPocket / 2 ( maximal infeed in Z )

V.L.MaxIncrementXY = V.G.WZ_AKT.R*0.9 ( maximal infeed in XY )

V.L.FeedRateZ = 150 ( plunging feedrate )

V.L.ContourID = 1 (Idendification number pocket contour)

#ENDVAR

; contour definition:

#CONTOUR BEGIN[ID = 1]

G1 G90 X90 Y20

G1 G91 Y40

G1 G91 X-20

G1 G90 X50 Y80

G1 X30 Y60

G161 G03 X30 Y20 I30 J40

G1 X90

#CONTOUR END

G0 ZV.L.RetractionPlane

; polynomial contouring for smooth movements

#CONTOUR MODE [DEV, PATH_DEV = V.G.WZ_AKT.R / 100]

G261

L CYCLE [NAME = SysMillContourPocket.ecy \

@P1 = V.L.SurfacePosition \

@P2 = V.L.RetractionPlane \

@P3 = V.L.SafetyClearance \

@P4 = V.L.DepthOfPocket \

@P5 = V.L.MaxIncrementZ \

@P6 = V.L.MaxIncrementXY \

@P21 = V.L.FeedRateZ \

@P31 = "Roughing" \

@P50 = V.L.ContourID \

]

G260

M30